Material guide

MDF feeds and speeds for CNC routers

Published chip loads for cutting MDF with 1/4" and 1/2" router bits, how MillCaliber's estimates compare, which bit type to choose, how to fix fuzzy edges, and how to handle MDF dust.

Last updated 24 October 2026 · Sources accessed 24 October 2026

Read this first: the figures below are published starting points from tool makers, plus MillCaliber's own estimates. MillCaliber has not run cutting tests on MDF, and its method has not yet been reviewed by an independent machining professional. The data for the exact bit you own takes priority. Make a test cut on scrap.

1. Quick answer

For a 1/4" two-flute bit, tool makers publish MDF chip loads of about 0.006–0.008 in per tooth (0.15–0.20 mm). Amana lists 0.0061 in per tooth for a 1/4" two-flute compression bit at 18,000 RPM and 220 in/min. These figures assume the makers' stated conditions: a CNC spindle at 18,000 RPM and a depth of cut equal to the bit diameter.

Work out the feed with feed = RPM × flutes × chip load. If your machine can't reach that feed, lower the RPM rather than the chip load, so each tooth still takes a full chip. Use a downcut bit for pockets and a compression bit for cut-outs if you need clean faces.

Open the calculator with MDF selected

2. Published starting points

Each figure below is for a specific tool series. Chip load depends heavily on the bit's geometry, so use the figure for the bit you actually run.

Bit (maker, series)DiameterFlutesChip load (in/tooth)Stated conditions
Amana solid carbide compression spiral1/4"10.006218,000 RPM, 110 in/min, depth 1 × D
Amana solid carbide compression spiral1/4"20.006118,000 RPM, 220 in/min, depth 1 × D
Amana solid carbide compression spiral1/2"20.011118,000 RPM, 400 in/min, depth 1 × D
Onsrud 57-200 downcut spiral (as listed by CNC Router Store)1/4"20.006–0.008Range for MDF
Onsrud 64-000 / 65-000 O-flute (as listed by CNC Router Store)1/4"10.004–0.006Range for MDF
Onsrud 48-700 (Onsrud MDF cutting data)1/2"20.006–0.008Worked example at 18,000 RPM: 216–288 in/min

Amana's 3-flute In-Presta production bits list much heavier chips (0.009–0.014 in per tooth at 1/4") for particleboard, MDF and melamine. Those are high-production tools, and the figures are not a guide for general-purpose bits on light machines.

These are the makers' recommendations for their own tools on CNC machines with production spindles. They are not results measured on desktop or belt-driven machines.

3. How MillCaliber's estimates compare

In the calculator, MDF shares the “Softwood / MDF” baseline: 1,800 SFM and 0.0060 in per tooth for a 1/4" bit on a rigid machine. These are MillCaliber's estimates for a 1/4" two-flute bit, adaptive pocketing at 50% width of cut, with each machine class's default limits:

Machine classRPMChip load (in/tooth)Feed (in/min)Note
Rigid / ball-screw24,0000.0060288In line with the published 1/4" figures
Semi-rigid benchtop16,6000.0045149.4RPM lowered to stay under the 150 in/min default feed limit
Desktop / belt-driven24,0000.0033158.4About half the published low end

The lower desktop and semi-rigid chip loads come from MillCaliber's machine factors (0.55 and 0.75). They are meant to reduce cutting force on less stiff machines, but they are heuristics that have not been validated. Being below a published example does not make a setting safer or better. A chip that is too thin can rub and burnish MDF, leaving fuzzy edges and dulling the bit faster (see section 7).

If your machine handles it, the tool maker's chip load is the better reference. To get closer to it without overloading a light machine, reduce depth of cut or stepover first, keep the chip load, and recalculate. The full method is on the Methodology page.

4. From chip load to feed rate

Feed (in/min) = RPM × number of flutes × chip load (in/tooth)

Example: 18,000 RPM × 2 flutes × 0.007 in = 252 in/min.

Many desktop machines can't cut at 252 in/min. Lower the spindle speed instead of lowering the chip load: 12,000 RPM × 2 × 0.007 in = 168 in/min gives the same chip. Lowering the feed alone at the same RPM thins the chip, which is a common cause of burnished, fuzzy MDF edges. MillCaliber applies the same rule when your max feed limits the result.

5. Choosing a bit

Bit typeWhat it does in MDFTypical use
Downcut spiralPushes fibres down, so the top edge stays clean. Chips pack into the cut rather than lifting out.Pockets, dados, engraving where the top face shows
Compression spiralUpcut at the tip and downcut above it, so both faces stay clean when the cut goes through the sheet.Through cuts and cut-outs in sheet goods
Upcut spiralLifts chips out well, but lifts surface fibres, so the top edge can be fuzzy.Roughing, deep slots where chip clearing matters more than the top edge
O-flute (single flute)Large chip space; Onsrud lists these for MDF at 0.004–0.006 in per tooth (1/4").Machines with a low max feed: one flute needs half the feed of two flutes for the same chip

With a compression bit, the first pass has to go deeper than the bit's upcut section. Otherwise the result is similar to cutting with an upcut bit (ToolsToday). Check the upcut length in the bit's specification. If your machine can't take a first pass that deep, ToolsToday suggests a standard upcut or downcut bit for profile cuts instead.

6. Depth of cut

Amana's and Onsrud's charts apply the same adjustment for deeper cuts:

  • Depth of cut up to 1 × bit diameter: use the chart chip load.
  • Depth of cut 2 × diameter: reduce the chip load by 25%.
  • Depth of cut 3 × diameter: reduce the chip load by 50%.

On a light machine, depth of cut and stepover are the main ways to reduce cutting force while keeping a full chip. MillCaliber's engagement guideline uses both; see Methodology.

7. Fixing fuzzy edges

MDF has no grain, so poor cuts fray rather than tear out. Where the fuzz appears points to the cause:

What you seeLikely causeTry first
Fuzzy top edgeAn upcut bit lifting surface fibresDowncut for pockets; compression for through cuts
Fuzzy bottom edgeA downcut bit pushing unsupported fibres off the undersideCompression bit and a flat spoilboard
Both edges fuzzyDull bit, or chip load well below rangeFresh bit first, then check the feed
Fuzz with a warm, polished wallThe edge is burnishing instead of cuttingRaise the feed into range, or replace a worn bit
Clean at first, fuzzy laterThe cutting edge is wearingReplace or sharpen the bit; consider coated tooling
Fuzz only in inside cornersFeed drops as the machine slows for the corner, so chips thinRound inside corners in the toolpath, or raise acceleration

Diagnosis adapted from CNC Router Store's guide to fuzzy MDF edges. For other symptoms (chatter, burning, broken bits), see Diagnosing problems.

8. Tool wear

The resin that binds MDF is abrasive and gradually rounds cutting edges. A rounded edge pushes fibres instead of cutting them, so edge quality drops even when settings haven't changed. If fuzz appears partway through a job, check the bit before changing the feed. Coated bits are sold for longer life in abrasive sheet goods; check the maker's specification for MDF.

9. MDF dust and health

Machining MDF makes fine dust. WorkSafe Victoria notes that wood dust has been classified by IARC as carcinogenic to humans, and that MDF's resin binder can contain formaldehyde. CPWR's MDF safety fact sheet lists these precautions:

  • Capture dust at the source: a dust shoe or extraction point as close to the bit as possible, connected to a suitable extractor.
  • Clean with a HEPA-filtered vacuum or wet methods. Don't use compressed air, which puts fine dust back in the air.
  • Ventilate the room: dust filters may not capture formaldehyde gas.
  • Respirators are the last line of defence, and need the right filter and a good fit.
  • Choose lower-emission panels where possible, such as boards labeled NAF (no added formaldehyde) or ULEF (ultra-low-emitting formaldehyde).

This is general information, not occupational health advice. Follow the board maker's safety data sheet and local workplace rules.

10. Bits for MDF

These links open Amazon search results for the bit types above. They are not specific products MillCaliber has tested. Compare the maker's chip load data before you buy.

As an Amazon Associate, MillCaliber earns from qualifying purchases. See the affiliate disclosure.

11. Sources

All accessed 24 October 2026. These sources are cited for their published figures and guidance; they do not endorse MillCaliber.